Table of Tools ACTUALLY on Haas as of July 13, 2007

Note: Max cutting speeds are approximate and conservative, we should note successes with higher speeds--put them both here and in the Tool Info table below.
All endmills are extended-length except where marked "short". In Unigraphics, where you set Cut Depths, set Initial, Maximum = maximum in table below. Set Minimum, Final to half of that number.

Tool #	Tool Description	Tool Diameter (mm)	Tool Reach (mm)	Max Cutting Depth (mm)	Max Cutting Speed, Wax (mm/min)	Max Cutting Speed, Urethane (mm/min)
1	Face mill	80	N/A	2	2000	200
2	empty			4
3	1/4" flat	6.35	~40	3	1000	400
4	1/8" flat	3.175	~25	2	250
5	1/16" flat-short	1.5875	6.35	1	1200
6	1/16" (0.062") ball	1.5875	25	0.5
7	Li's undercut tool
8	1/4" ball	6.35	~40	3	600
9	1/16" (0.062") long flat	1.5875	21	1	150
10	1/32" (0.031") long	0.7938	7.781	0.5	200? 250 is too high	<200
11	0.015" flat-temporary	0.381
12	1/32" flat-short	0.7938	2.38	0.5	500	500
15	appears to be broken

---

Table of Info for Tools

This table gives the general info (tool reach, max. cutting depth, etc.) for all the different tools we could potentially have in the HAAS. Don't change this except if you are able to run the tools at faster cutting speeds--in which case do update it so we can all run the tools faster!
All tools are extended-reach except where indicated "short".

Tool Description	Tool Reach (mm)	Max Cutting Depth (mm)	Max Cutting Speed, Wax (mm/min)	Max Cutting Speed, Urethane (mm/min)	Part Number
Face mill	N/A	2	2000	200
1/2" flat		4
1/4" flat	~40	3	1000	400
1/8" flat	~25	2	250
1/16" flat (12mm)	12	1	150?
1/16" flat (21mm)	21	1	150?		Harvey 13662
1/32" flat	10	0.5	250?	??
1/4" ball	~40	3	600
1/8" ball	~25	2	200
1/16" ball	~12	1	100
1/32" ball		0.5	50
1/16" flat-short	6.35	1	1200
1/32" flat-short	2.38	0.5	500	500
0.015"flat

---

Cutting Parameters: Feeds and Speeds

(See Machinists Handbook or http://www.endmill.com/pages/training/spdfeed.html)
Depth of Cut: No greater than tool diameter. 1/2 of tool diameter is safer.
Width of Cut: No greater than 2/3 of tool diameter. 1/2 is safer.

• CS=
  • 500(Plastic)
  • 300(Aluminum)
  • 200(Brass)
  • 100(Bronze)
  • 50(Steel)
• ChipLoad=
  • .0002 -.0005 (ToolDiameter<1/8")
  • .0002 -.001 (ToolDiameter<1/4")
  • .0005 -.002 (ToolDiameter<=1/2")
  • .002 -.005 (PRL Recommendation, not as conservative for small bits)
• RPM=CS*3.82/ToolDiameter
• RPM=CS*4/ToolDiameter(PRL Equation)
• MMPM(millimeters per minute)=RPM*ChipLoad*#Flutes*25.4

Tool Dia	Chip Load per tooth	RPM (spindle speed)	Feed Rate for Al, plastic, wood (mm/min) at 6000 rpm
1/16	.0002 -.0005	12000	60-150
1/8	.0002 -.001	6000	60-300
1/4	.0005 -.002	3056-9168	150-600